MACHINING.TRPrecision Machining. Engineered in Turkey.
Micrometer measurement of a turned brass part
  1. Home
  2. Engineering
  3. Tolerances & Fits

Engineering

Tolerances and fits

A tolerance defines how much a dimension may vary while the part still works. Choosing it is an engineering decision with direct consequences for manufacturing method, inspection and cost.

IT grades

ISO 286-1 defines standard tolerance grades IT01 to IT18. The tolerance value depends on the grade and the nominal size: larger parts get larger tolerances for the same grade.

Nominal size (mm)IT5IT6IT7IT8IT9IT10IT11
0 – 3461014254060
3 – 6581218304875
6 – 10691522365890
10 – 1881118274370110
18 – 3091321335284130
30 – 501116253962100160
50 – 801319304674120190
80 – 1201522355487140220
120 – 18018254063100160250
180 – 25020294672115185290
250 – 31523325281130210320
315 – 40025365789140230360
400 – 50027406397155250400
Standard tolerance values in µm per ISO 286-1. Shown for orientation — always confirm against the current edition of the standard.

Fits

A fit combines a hole and a shaft tolerance. In the hole-basis system the hole is usually H (lower deviation zero) and the shaft letter defines the fit.

Fit (hole basis)TypeTypical use
H7/g6Clearance (sliding)Precise sliding parts, locating pins
H7/h6Clearance (locational)Parts assembled by hand, spigots
H7/k6TransitionGears and couplings on shafts, keyed
H7/n6Transition / light interferenceFirm location, bushings
H7/p6Interference (press)Pressed bearings and bushings
H8/f7Clearance (running)Plain bearings, general running fits
Common combinations. Final selection depends on materials, temperatures, lengths and assembly method.

Use the ISO fit calculator to compute limits, clearance and interference.

General tolerances

ISO 2768-1 gives default tolerances for dimensions without individual tolerances (classes f, m, c, v). ISO 2768-2 (H, K, L) covers geometrical tolerances; it is being replaced by ISO 22081. A drawing note such as ISO 2768-mK means medium linear and K geometric general tolerances.

Range (mm)fmcv
0.5 – 3±0.05±0.1±0.2—
> 3 – 6±0.05±0.1±0.3±0.5
> 6 – 30±0.1±0.2±0.5±1
> 30 – 120±0.15±0.3±0.8±1.5
> 120 – 400±0.2±0.5±1.2±2.5
> 400 – 1000±0.3±0.8±2±4
ISO 2768-1 linear dimensions (excluding broken edges). Verify against the current edition.

What tolerances cost

Tighter tolerances need more stable processes, slower finishing, better measurement and sometimes grinding. As a rule of thumb, every step tighter than the process naturally achieves adds cost — and below about IT6 many features require grinding or honing. Ask: what happens functionally if this dimension is at its limit?

Size and geometry

Under ISO 8015 (independency principle) size tolerances do not control form. If a fit needs perfect form at maximum material, specify the envelope requirement Ⓔ or a geometrical tolerance. US drawings to ASME Y14.5 apply Rule #1 by default.

Enquiry

Have a drawing to review?

Send your 2D drawing and 3D model with quantities, material and required documents. An engineer reviews manufacturability, tolerances and inspection before quoting.

What to include in your enquiry